gbradley Posted July 23, 2014 Share Posted July 23, 2014 I need help placing a dimension at the Theoretical Sharp Corner. I understand how to do it with two angles and a straight line by using the Intersection. I am having trouble with two angles and a curved line. Any suggestions? Autodesk Inventor 2015 Quote Link to comment Share on other sites More sharing options...
JD Mather Posted July 23, 2014 Share Posted July 23, 2014 Are you simply trying to dimension the X distance? Select the two endpoints (not the curves). Quote Link to comment Share on other sites More sharing options...
easymike29 Posted July 23, 2014 Share Posted July 23, 2014 If you tolerance the overall height, the angles and the .1009 dimension,you needn't be concerned with the X dimension. It becomes a reference dimension. Gene Quote Link to comment Share on other sites More sharing options...
gbradley Posted July 23, 2014 Author Share Posted July 23, 2014 Yes the X distance, and I don't have pick points at the intersection of the Angled lines and the top radius. They show in this sketch, but I don't see them in the View. Quote Link to comment Share on other sites More sharing options...
gbradley Posted July 23, 2014 Author Share Posted July 23, 2014 If you tolerance the overall height, the angles and the .1009 dimension,you needn't be concerned with the X dimension. It becomes a reference dimension. Gene Hi Gene, Yes, thanks, that is what I did, but I would like to see what the Reference dimension is, so that is why I want to be able to place it. Quote Link to comment Share on other sites More sharing options...
ConMan Posted July 23, 2014 Share Posted July 23, 2014 It's a lot of screwing around but you could always select the view, start a sketch and draw a line and arc segment to project the two features to a sharp point. Exit the sketch and dimension to the sharp points. If you want you can go back and edit the sketch once you've placed the dimension and make the extension line and arc sketch only so they don't show up on the drawing. Hopefully someone else has a more elegant fix, but you could always kludge it this way. Quote Link to comment Share on other sites More sharing options...
JD Mather Posted July 23, 2014 Share Posted July 23, 2014 Yes the X distance, and I don't have pick points at the intersection of the Angled lines and the top radius.They show in this sketch, but I don't see them in the View. That is the image you should have posted originally - I couldn't see those tiny fillets in the original image. In a case like that - I create the sketch at the part level and then Include the sketch and the dimensions when creating the drawing. Quote Link to comment Share on other sites More sharing options...
gbradley Posted July 23, 2014 Author Share Posted July 23, 2014 Got it Thanks JD I put a reference dimension in the Sketch and then Retrieved that dimension on the view Works great! Quote Link to comment Share on other sites More sharing options...
easymike29 Posted July 23, 2014 Share Posted July 23, 2014 In your last drawing the .1009 dimension is not specified to be measured at the theoretical sharp corners. The machinist/toolmaker/mold maker or ? is not supposed to make assumptions. Gene Quote Link to comment Share on other sites More sharing options...
lrm Posted July 23, 2014 Share Posted July 23, 2014 Place the .1009 and .1772 dimensions before adding the 0.04 radius then you will be dimensioning to the TSC. Add a note as such to the dimension line. Quote Link to comment Share on other sites More sharing options...
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