Laurel Posted December 7, 2009 Share Posted December 7, 2009 This inventor drawing is one that I have submitted as part of a course I am attending. I have been asked to resubmit it with an amendment - The rib through which the section plane cuts, should not be hatched on the cross-section view. Could someone please explain how I can achieve this, as I cannot seem to get inventor to produce this view. Thanks. Quote Link to comment Share on other sites More sharing options...
JD Mather Posted December 7, 2009 Share Posted December 7, 2009 Are you familiar with the rules for section views with ribs? Right click on the hatch and hide visibility. Make sure the boundary of the view is highlighted and hit S on the keyboard. Project Geometry and select the edges needed to rebuild boundary of rib. Right mouse button Done. Add the sketch lines for the boundaries of the rib (you will probably want to change the line weight of the sketched boundaries as well). Fill the bounded area with desired hatch. Exit sketch If you can't figure it out attach your files here. Quote Link to comment Share on other sites More sharing options...
pgcust Posted December 7, 2009 Share Posted December 7, 2009 JD. Could he just move the section line to the side of the rib? chris Quote Link to comment Share on other sites More sharing options...
JD Mather Posted December 7, 2009 Share Posted December 7, 2009 JD.Could he just move the section line to the side of the rib? chris I guess that might work as an easy workaround - would require a couple of off-sheet views. The view on sheet should show the section line as he has it though. Quote Link to comment Share on other sites More sharing options...
pgcust Posted December 7, 2009 Share Posted December 7, 2009 I would have thought the original section is correct,why would he want a section that isnt true? Quote Link to comment Share on other sites More sharing options...
JD Mather Posted December 7, 2009 Share Posted December 7, 2009 I would have thought the original section is correct,why would he want a section that isnt true? If you consult any drafting standards book it is standard practice to not show ribs in section even though the cutting plane goes through the rib. The purpose is for clarity in conveying 3D information in a 2D medium (paper). Try it and you will see it does look much better aesthetically. This is one of the arguments that those who don't know how to do 3D CAD will present against Inventor and the like - it won't create proper sections (actually SolidWorks will) according to standard practice. Of course it can be done just takes a bit of user input. Quote Link to comment Share on other sites More sharing options...
pgcust Posted December 7, 2009 Share Posted December 7, 2009 You learn something new everyday.Has this standard changed with advent of cad programs? JD,are there any tests around to check on my level of inventor use? Quote Link to comment Share on other sites More sharing options...
JD Mather Posted December 7, 2009 Share Posted December 7, 2009 This is the way standard practice normally shows ribs in section. Quote Link to comment Share on other sites More sharing options...
Laurel Posted December 8, 2009 Author Share Posted December 8, 2009 Thank you everyone for your input (especially JD for showing me how to do this ). It's alway nice when one of your posts starts a debate that might show other people how to do it too. Here's my amended drawing. Quote Link to comment Share on other sites More sharing options...
Enfiel3D Posted December 22, 2009 Share Posted December 22, 2009 Is there any other solution to wipe out portion of the hatch without hiding automatic hatch and recreating boundary for sketch-based hatching? Quote Link to comment Share on other sites More sharing options...
jori Posted March 7, 2010 Share Posted March 7, 2010 i like this drawing iam new student today we took about rib and sectional views Quote Link to comment Share on other sites More sharing options...
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